PCB_Dlg-FanoutPropertiesDlgFanout Options_AD

您正在阅读的是 19. 版本。关于最新版本,请前往 PCB_Dlg-FanoutPropertiesDlg((Fanout Options))_AD 阅读 22 版本

The Fanout Options dialog
The Fanout Options dialog

Summary

This dialog allows you to specify fanout and escape routing options. Typical fanout behavior is for used inner pads to first be fanned out using the traditional dog-bone (a short route with a via on the end) to access another layer, and then from the via, they are escape-routed out just beyond the edge of the device, working through the available routing layers until all pads have been escape-routed. Ultimately, this makes routing connections to them much easier.

Fanout and escape routing is done in accordance with the applicable design rules, including the Fanout Control rule, Width rule, Routing Via Style rule, Routing Layers rule, and the Clearance rule.
To fanout the pads of a component, make sure that there is no polygon pours under this component on any layer. Polygons can be shelved before creating fanouts and restored afterward.

Access

The dialog is accessed from the PCB Editor in one of the following ways:

  • Use any of the commands on the Route » Fanout sub-menu.
  • Right-click over a placed component in the design space then choose the Component Actions » Fanout Component command from the context menu.

Options/Controls

Choose Fanout Properties

  • Fanout Pads Without Nets - enable this option to fanout pads from the component even if they have no nets assigned to them. When this option is disabled, only pads with nets assigned will be fanned out.
  • Fanout Outer 2 Rows of Pads - enable this option to fanout pads from the component including the outer two rows (which are usually easily routed).
Fanning out a component will drop vias as required to enable connection. If drill-pairs have been configured for layers and the Update fanout using Blind Vias option is enabled, blind vias will be dropped, otherwise, through-hole vias will be used.
  • Include escape routes after fanout completion - enable this option to add escape routing to each fanout. Escape routing places tracks onto the fanout vias and component pads, bringing them out to the edges of the component, to make routing connections to them easier.

BGA Escape Route Options

The options in this region of the dialog only become available when the Include escape routes after fanout completion option is enabled.

  • Update fanout using Blind Vias (BGA escape routing only) - enable this option to drop blind vias between configured drill-pair layers in the layer stack. When this option is disabled, only through-hole vias will be dropped regardless of drill-pair layer settings.
If there are no drill layer pairs defined to be able to use blind vias, this option will appear as Cannot Fanout using Blind Vias (no layer pairs defined).
  • Escape differential pair pads first if possible (same layer, same side) - enable this option to fanout and escape route any assigned differential pair nets together, and before performing other fan out operations, effectively keeping their routes together. The fanout will place escape routing tracks on to the same layer and as adjacent as possible.
If you find an issue, select the text/image and pressCtrl + Enterto send us your feedback.

软件的功能取决于您购买的Altium产品级别。您可以比较Altium Designer软件订阅的各个级别中包含的功能,以及通过Altium 365平台提供的应用程序所能实现的功能。

如果您在软件中找不到某个讨论过的功能,请联系Altium销售团队以获取更多信息。