Search In: Doc:Documentation: Altium CircuitStudio
Altium DesignerAltium 365Altium MCAD CoDesignerAltium On-Prem Enterprise ServerAltium CircuitMakerAltium CircuitStudioCompany DashboardAltium Infrastructure Server
Close
Suche Search on Documentation
Documentation CircuitStudio Documentation ... PCB Dialogs

Fanout Options

Created: Dezember 16, 2024 | Updated: August 13, 2018
Other Related Resources
Autorouting Tools
Layer Stack Manager (Dialog)
Drill-Pair Manager (Dialog)

Parent page: PCB Dialogs

The Fanout Options dialog

Summary

The Fanout Options dialog provides controls to specify fanout and escape routing options. Typical fanout behavior is for used inner pads to first be fanned out using the traditional dog-bone (a short route with a via on the end) to access another layer, then from the via, they are escape-routed out just beyond the edge of the device, working through the available routing layers until all pads have been escape-routed. Ultimately, this makes routing connections to them much easier.

Fanout and escape routing is done in accordance with the applicable design rules, including the Fanout Control rule, Routing Width rule, Routing Via Style rule, Routing Layers rule, and the Electrical Clearance rule.

Access

The dialog is accessed from the PCB Editor in the following ways:

  • Use any of the commands on the menu associated to the Tools | AutoRoute |  button.
  • Right-click over a placed component in the design workspace then choose the Component Actions » Fanout Component command from the context menu.

Options/Controls

Choose Fanout Properties

  • Fanout Pads Without Nets - enable this option to fanout pads from the component even if they have no nets assigned to them. When this option is disabled, only pads with nets assigned will be fanned out.
  • Fanout Outer 2 Rows of Pads - enable this option to fanout pads from the component, including the outer two rows (which are usually easily routed).
Fanning out a component will drop vias as required to enable connection. If drill-pairs have been configured for layers and the Update fanout using Blind Vias option is enabled, blind vias will be dropped, otherwise, through-hole vias will be used.
  • Include escape routes after fanout completion - enable this option to add escape routing to each fanout. Escape routing places tracks onto the fanout vias and component pads bringing them out to the edges of the component to make routing connections to them easier.
    • BGA Escape Route Options
      • Update fanout using Blind Vias (BGA escape routing only) - enable this option to drop blind vias between configured drill-pair layers in the layer stack. When this option is disabled, only through-hole vias will be dropped regardless of drill-pair layer settings.
If there are no drill layer pairs defined to be able to use blind vias, this option will appear as Cannot Fanout using Blind Vias (no layer pairs defined).
  •  Escape differential pair pads first if possible (same layer, same side) - enable this option to fanout and escape route any assigned differential pair nets together and before performing other fan out operations, effectively keeping their routes together. The fanout will place escape routing tracks on to the same layer and as adjacent as possible.

 

If you find an issue, select the text/image and pressCtrl + Enterto send us your feedback.
Content