Preparing Printed Data

Print-based output for your PCB project in Altium Designer is available through creating a output job configuration file (*.OutJob). When you create a job output, there is a range of manufacturing documentation available for output including common two-dimensional PCB printouts, such as a composite drawings and schematic drawings. 2D print output is configured in the PCB Printout Properties dialog. 3D PCB printout (PCB 3D Prints) is configured in the PCB 3D Print Settings dialog.

To create an output job file, click File » New » Output Job File from the main menus. The new Output Job File will appear as a new file in the OutJob Editor window.

Output jobs are configured as an OutJob file, giving you full control over print-based output.

Configuring 2D Print-based Output

When you are ready to print documentation from your OutJob, access the PCB Printout Properties dialog (right-click on the desired output then choose Page Setup to open the appropriate Print Properties dialog, then click the Advanced button). In the PCB Printout Properties dialog that opens, you can define and manage the printout(s) required for the specific print-based documentation you want to generate.

The main area of the dialog is divided into three columns:

• Printouts & Layers - lists the currently defined printouts and their constituent layers.
• Include Components - enables you to control which components are included in the associated printout.

• Printout Options - enables you to control additional options with respect to the associated printout.

Adding a New Printout

A new printout can be added to the current configuration by choosing the Insert Printout command from the PCB Printout Properties dialog's right-click menu.

The printout will be added beneath existing printouts and will be given a default name of New PrintOut 1. By default, all options in the Include Components column will be enabled.

Double-click on a printout to open the Printout Properties dialog in which you can configure the properties of a printout/printout set.

Configuring a Printout

A newly added printout can be configured (and an existing printout's configuration can be edited) by accessing the associated Printout Properties dialog. This dialog is accessed either by double-clicking on the name field for the printout (in the Printouts & Layers column) or by right-clicking on the name field then choosing Properties from the resulting menu.

• The Printout Name field allows you to change the name for the printout as required to assign a more meaningful name that will readily identify the nature and purpose of the printout. You can also change the name for a printout directly in the PCB Printout Properties dialog. Click once on the name field for the required printout to enter a new name.
• The Components region allows you to control which components are included on the printout. For example, if the printout is concerned with only layers on the top side of the board, you might want to show only components placed on the top layer and components that have pads on both top and bottom layers (e.g., PCB Edge Connectors).
• The Options region provides advanced print-related options, such as whether font substitution should be used where alternative fonts are used for the printout in place of the three default fonts used in the PCB Editor (Default, Serif, Sans Serif). Specification of such fonts is performed in the PCB Print Preferences dialog (see the Setting Print Preferences section).
• The Pad Display Options region provides options that allow you to control the display of pads on the printout. i.e. whether or not pad numbers and associated nets are shown and the font size used for the text.
• The Layers region is the 'heart' of printout configuration, providing the necessary controls to add, edit, and order the layers that are to make up the printout. Whether adding a new layer (click Add) or editing an existing one (click Edit),  the  Layer Properties dialog will open in which you can configure the layer as required.

Adding a New Layer

A new layer can be added to a printout in one of the following ways:

• While configuring the parent printout using the Printout Properties dialog: Use the Add button to add a new layer to the Layers list. The new layer will appear at the bottom of the list but controls are provided in this dialog for changing the ordering of layers.
• Directly from within the PCB Printout Properties dialog: Right-click within the area of the printout you wish to add a new layer to and choose Insert Layer from the resulting menu. The new layer will be added beneath any existing layers for that printout. You cannot change the layer ordering in the PCB Printout Properties dialog. This can only be achieved from within the Printout Properties dialog.

Configuring a Layer

A newly added layer can be configured (or the configuration of an existing layer can be edited) by accessing the associated Layer Properties dialog. This dialog appears directly when adding a new layer. To access the dialog for an existing layer either:

• Access the Printout Properties dialog for the parent printout, select the layer then press the Edit button.
• Double-click directly on the layer's name in the Printouts Layers column of the PCB Printout Properties dialog.

If you are adding a new layer to a printout, first select the layer you would like to add from the Print Layer Type drop-down list. The list contains all currently defined layers for the source PCB document, allowing you to include any PCB layer on a printout. The central regions of the dialog provide controls to determine how the primitives on that layer are displayed on the printout - either in Full, Draft (outline), or Hide (off) mode. This gives you complete control over what appears on the printed page.

Consider, as an example, an assembly drawing that includes the following layers:

• Component overlay
• Top layer (for surface mount pads)
• Multilayer (for through-hole pads)

The top layer would be configured to display the component primitives so the surface mount pads are visible and hide the free primitives so the routing is not visible. The multilayer would also be configured to display the component primitives so the through-hole component pads are visible, and hide the free primitives so that the vias are not visible.

Setting Print Preferences

Click the Preferences button at the bottom left of the PCB Printout Properties dialog to access the PCB Print Preferences dialog. All options defined in this dialog apply to each print-based output that can be generated.

Colors & Gray scales

This region allows you to control the coloring that is used for each possible layer than can be printed. For each layer, you can define the color used when printing in gray scale or color. Click on the left-hand color swatch to access the range of gray scale shades.

Click on the right-hand color swatch to access the Choose Color dialog, from where you can choose from a range of predefined colors or create your own, custom color.

Press the Retrieve Layer Colors From PCB button in the PCB Print Preferences dialog if you want to print using the same colors configured for the PCB design in the PCB Editor.

Include on New Printouts

In addition to adding mechanical layers individually to a printout, you can also automatically include them in all printouts when the print job(s) for the parent document type is sent to the nominated printing device. Use this region of the dialog to enable/disable each of the mechanical layers for printing, as required.

Font Substitutions

Each of the three standard fonts used in the PCB Editor (Default, Serif and Sans Serif) can be substituted for a different Windows font when the printout is generated. Use the options in this region of the dialog to specify and enable substitution fonts.

Click on the  button next to the required font field to access the standard Windows Font dialog in which you can choose the substitution font required.

When you click OK , the name of the font will be inserted into the font field.

Options

The Print Keepout Objects option gives you full control over whether keepout designated design objects are included on the printed document or not.

Enable the Use Net override color checkbox if you want to use the net override color in your printout.

Right-click Menu

The following list of commands are available from the right-click menu, accessed from anywhere within the PCB Printout Properties dialog:

• Create Final - use to quickly create a complete, predefined final artwork print-set for the source PCB document.
• Create Composite - use to quickly create a predefined multi-layer composite print for the source PCB document.
• Create Power-Plane Set - use to quickly create predefined power-plane drawings for the source PCB document.
• Create Mask Set - use to quickly create predefined solder/paste mask drawings for the source PCB document.
• Create Drill Drawings - use to quickly create a predefined set of drill drawings and guides for the source PCB document.
• Create Assembly Drawings - use to quickly create predefined assembly drawings for the source PCB document.
• Create Composite Drill Guide - use to quickly create a predefined composite drill drawing for the source PCB document.
• Insert Printout - use to insert a new printout for the print-based output currently being configured.
• Insert Printout Set - use to create a printout that includes all layers combined onto one layer. Additional layers and layer classes can then be added.
• Insert Drill Printout Set - use to create a new drill printout. Layers and layer classes can then be inserted into the drill printout.
• Insert Layer - use to insert a new layer into the focused printout. The layer will be added to the bottom of the current list of layers that exist for that printout.
• Insert Layer Class - use to insert a new layer class into the focused printout.
• Move Up - use to move items up within a column.
• Move Down - use to move items down within a column.
• Delete - use to remove the focused layer from its parent printout, or the focused printout from the print-set currently being configured. You will be prompted for confirmation of the deletion. You will be prevented from deleting all layers from a printout and all printouts from a print-set.
• Properties - use to access either the Layer Properties dialog or Printout Properties dialog, depending on whether the focused entry is a layer or a printout, respectively.
• Preferences - use to access the PCB Print Preferences dialog in which you can define global options that apply to all print-sets.

Configuring 3D Print-based Output

The PCB 3D Print Settings dialog enables you to select or create 3D printouts of your PCB for inclusion in the job output file. Remember, you can have multiple instances of any printout (use the Add New Documentation Output control from the OutJob in the Output Containers region to do this), which is particularly useful for 3D since you can print out views of the board from differing perspectives if you wish.

The dialog is divided into four regions:

• Render Resolution - includes options for the quality of the "picture" of the 3D model to be printed. The available resolutions are not printer dependent.
• View to Print - enables you to select from flat views of the board, that is, the camera perspective perpendicular to the board, either from above or from below, or a Custom view.
• View Configuration - enables you to apply the current view configuration for surface colors, visibility. opacity, and board thickness.
• Preview - shows you exactly what will be printed.

Creating Custom 3D Printouts

A custom view of your board can include it being rotated to an angle, zoomed, have various settings for surface colors, visibility, opacity, and board thickness. You can use these options to generate views that provide high levels of detail to highlight areas of your design or even create effects.

To create a custom 3D view of your board as a printout, perform the following steps:

1. Go to the PCB Editor window and enter 3D mode [shortcut: 3 ].
2. Use the 3D view controls to achieve the desired perspective.
3. Return to the job output file and double-click anywhere on the PCB 3D Print row (or right-click on it and select Configure from the shortcut menu) to open the PCB 3D Print Settings dialog.
4. Click the Custom option then press the Take Current Camera Position button. The Preview pane will update with the new perspective.
5. Click OK to apply the custom setting to the current PCB 3D printout.

If you would like to apply custom surface colors, etc., perform the following steps:

1. Go to the PCB Editor window and open the View Configuration panel (View » Panels » View Configuration from the main menus, or click the Panels button (at the bottom right of the main editor » View Configuration, or [shortcut L ].
2. Set the options required. Note that you do not have to save the options to apply it to a PCB 3D printout.
3. Return to the job output file, open the PCB 3D Print Settings dialog, enable the Custom option then press the Take Current View Configuration button. The Preview pane will update with the new view configuration settings. Once you apply the view configuration, it will apply to all of the View to Print options.
4. Click OK to apply the view configuration to the current PCB 3D printout.
5. Save the OutJob file to keep any new 3D printouts.

Tips

Print-based output can be generated in the following ways:

• Using an appropriately-configured output generator defined in an Output Job file (*.OutJob): Output will be generated upon running the configured output generator.
• Directly from within the active PCB document using the File » Print menu command: Output will be generated for the currently enabled default print set.

Configuration options defined here are distinct and separate from those defined for the same output type in an Output Job file. In the case of the former, the settings are stored in the project file; for the latter, they are stored in the Output Job file.

Setup options accessed from the PCB Editor's File menu with respect to page and printer are also separate from those defined when accessed from within an Output Job file. Again, the former will be stored with the project file, the latter with the Output Job file.